Features that cut through multiple parts in a model or Assembly.
Assembly features are very similar to existing part features except they can affect multiple parts, are created in the context of an assembly/scene, and the feature definitions do not pass down to each part. Assembly features can be Extruded Cuts, Spin Cuts, or Custom Hole Shapes. Assembly Features are by definition, a machining process that is processed on the assembled component and not performed on each individual component.
Note: The Assembly Feature Scope can be modified at a later time by right-clicking on the Assembly Feature (in the scene or scene browser) and selecting Edit Assembly Feature Scope. Select part/assemblies to add/remove and select ok. In addition, in the scene browser, drag part onto the Assembly Feature Shape to add to the feature scope (right-click on a part in the scene browser under the Assembly Feature and select Remove from Assembly Feature Scope to remove).
Assembly Features that are patterned, maintain identical Feature Scope across the master and dependant instant shapes.
Linked instances of Assembly Features can have different a Feature Scope on each instance, however the shape geometry will maintain the link.
Note: Assembly Features are not represented on external linked part/assembly instances when opened outside of the context where the assembly feature resides. Assembly Features do not apply to individual linked parts unless converted to part features.
Multiple Part Features are similar to Assembly Features since they affect multiple parts, however multiple part features will reflect in each individual part definition. You can convert Assembly Features into part features by right-clicking on the Assembly Feature and selecting Convert to Part Features.
Assembly Features (set as empty) and Parts/Assemblies together can be drag & dropped into a Catalog. On drop from the Catalog, the Feature Scope Options will be displayed for the Assembly Feature and then the entire group containing the assembly feature and the parts/assemblies will be dropped. This capability will allow users the ability to drop complicated assemblies that remove material from other parts/assemblies on drop from a catalog (Example would be a window frame drop onto a wall or frame members).
Note: The location of the components will be based on the anchor location of the first selected shape in the group when selecting to drag and drop into the catalog.